I am running a closed system multiphase buoyancy problem in Fluent where the density of the liquid phase is described by the Boussinesq model. Is it possible to define a thermal expansion coefficient that varies with temperature? This property seems to only allow constant values. This is the case even when a UDF definition is available


January 25, 2023 at 7:16 amFAQParticipant
The Boussinesq model is the only variable density model that treats density as a constant in the equations. (The second term in the equation below is implemented as a momentum source term.) rho(T) = rho(To) + [d(rho)/d(T)]@To * (T â€“ To) The assumption is that rho(T) can be expressed as above at a given reference temperature, To (entered in operating conditions). The corresponding density is rho(To) (entered in materials) and the corresponding thermal expansion coefficient is beta(To). The derivative in the second term, [d(rho)/d(T)]@To is related to the thermal expansion coefficient by 1*beta(To)*rho(To). The Boussinesq approximation for density is is part of a Taylor series expansion, and would theoretically stop making sense if the derivative were taken at arbitrary T instead of prescribed To. To is generally set at the midpoint of the temperature range for the problem. Unless the temperature range is very large, using a singlevalued beta at the evaluated at the midpoint is normally quite accurate. Since the second term, 1*beta(To)*rho(To)* (T â€“ To) is treated as a momentum source term in the Boussinesq model, it would be possible to isolate this and implement your own using a DEFINE_SOURCE UDF. To to this: 1. Set the material density to constant rho(To) 2. Deactivate gravity so that the effect of the source term on the fluid phase is not duplicated 3. Define a source term equal to g*beta(T)*rho(To)* (T â€“ To) using DEFINE_SOURCE. NOTE: If the other phase has a slip velocity defined, this will have to be modified with DEFINE_VECTOR_EXCHANGE_PROPERTY UDF to account for the missing effect of gravity.

Introducing Ansys Electronics Desktop on Ansys Cloud
The Watch & Learn video article provides an overview of cloud computing from Electronics Desktop and details the product licenses and subscriptions to ANSYS Cloud Service that are...
How to Create a Reflector for a Center HighMounted Stop Lamp (CHMSL)
This video article demonstrates how to create a reflector for a center highmounted stop lamp. Optical Part design in Ansys SPEOS enables the design and validation of multiple...
Introducing the GEKO Turbulence Model in Ansys Fluent
The GEKO (GEneralized KOmega) turbulence model offers a flexible, robust, generalpurpose approach to RANS turbulence modeling. Introducing 2 videos: Part 1Â provides background information on the model and a...
Postprocessing on Ansys EnSight
This video demonstrates exporting data from Fluent in EnSight Case Gold format, and it reviews the basic postprocessing capabilities of EnSight.
 Defining heat transfer coefficient (HTC)
 Simulating Battery Pack Cooling System Using Ansys Fluent
 Thermal Analysis of a Radiator Using Ansys Fluent
 ANSYS Fluent Student: Conjugate Heat Transfer in a Heat Sink
 ANSYS Fluent: Overview of the Mapped Interface Technique for CHT Simulations (18.2)
 How to set up a heat source in CFX in a subdomain that results in a constant temperature
 Where do I enter radiation properties such as emissivity/absorptivity, are there any recommended values for certain surfaces, and where do I find them?
 What is the difference between internal and external emissivity?
 How to solve the warning: “Warning: zone of type interior found between different solids!”
 What are the TUI commands to enable / disable Shell Conduction?
Â© 2024 Copyright ANSYS, Inc. All rights reserved.