

July 26, 2024 at 3:28 amjeremy leongSubscriber
Hi, I have a problem when I solve the residual vectors in modal analysis. Could anyone give me some help, please? Thanks in advance.
I want to solve the residual vectors of a largescale 3D FEM and output them together with the modeshapes in MMF format. I know the residual vectors can be calculated in ANTYPE,MODAL and RESVEC should be activated. And actually I successfully obtained a residual vector under one concentrated force. But according to the theory of residual vectors method presented in Section 14.8.5 of Theory Reference, they are calculated by a matrix of multiple concentrated forces. So my question is how to define this forces matrix to obtain all residual vectors under multiple concentrated forces. The attempt I have made is shown below:
1)my APDL of computed a residual vector under one concentrated force
/SOL
ANTYPE,2
MODOPT,LANB,NUM_FREQ,0,0,,OFF
SOLVE
FINISH/SOL
ANTYPE,2,RESTART
MXPAND,NUM_FREQ, , ,0Â
RESVEC,ONÂ Â Â Â Â Â Â Â Â Â Â Â Â Â Â Â Â !RESIDUAL VECTOR METHOD FOR HIGHER FREQUENCY MODES
D,21653,ALL,SUPPORTÂ Â Â Â Â Â Â Â !SPECIFY PSEUDOCONSTRAINTS TO PREVENT RIGIDBODY MOTION
D,21965,ALL,SUPPORT Â Â Â Â Â Â Â Â !SPECIFY PSEUDOCONSTRAINTS TO PREVENT RIGIDBODY MOTION
num_NODE_=node_num(1)
F_DOF_INDEX_=F_DOF_INDEX(1)
F,num_NODE_,F_DOF_INDEX_,1Â Â Â !Generate load vector
SOLVE2) use the RESTART of MODAL ANALYSIS
I try to define every concentrated force in every step of RESTART to copmpted the residual vectors respectively. But in the second RESTART, an error occurs:Â
Â "Residual vectors (RESVEC command) were calculated during the first Â Â Â
Â modal analysis. Â The modal analysis cannot be restarted. Â If you need Â Â
Â to restart a modal analysis, make sure you only do the mode extraction Â
Â (and possibly expansion) during the first analysis without generating Â Â
Â residual vectors."I guess this is due to the second residual vector's calculation need to call the Jobname.mode to get the modeshapes withoutÂ any resiudal vectors, however, Â Jobname.mode have one residual vector after first RESTART. My APDL is as follows:
/SOL
ANTYPE,2
MODOPT,LANB,NUM_FREQ,0,0,,OFF
SOLVE
FINISH/SOL
ANTYPE,2,RESTART
MXPAND,NUM_FREQ, , ,0Â
RESVEC,ONÂ Â Â Â Â Â Â Â Â Â Â Â Â Â Â Â Â !RESIDUAL VECTOR METHOD FOR HIGHER FREQUENCY MODES
D,21653,ALL,SUPPORTÂ Â Â Â Â Â Â Â !SPECIFY PSEUDOCONSTRAINTS TO PREVENT RIGIDBODY MOTION
D,21965,ALL,SUPPORT Â Â Â Â Â Â Â Â !SPECIFY PSEUDOCONSTRAINTS TO PREVENT RIGIDBODY MOTION
num_NODE_=node_num(1)
F_DOF_INDEX_=F_DOF_INDEX(1)
F,num_NODE_,F_DOF_INDEX_,1Â Â Â !Generate the first load vector
SOLVEFDELE,ALL,ALLÂnum_NODE_=node_num(2)F_DOF_INDEX_=F_DOF_INDEX(2)F,num_NODE_,F_DOF_INDEX_,1 Â !Generate the second load vectorSOLVEÂAnother method I guess is that a restarted modal analysis to compute normal modes is needed before solving every residual vectors but this procedure is timeconsuming. 
July 26, 2024 at 1:58 pmdloomanAnsys Employee
It's not necessary to do restarts.Â You can issue modcont,on and then do multiple solves in the modal.Â Only the first solve will do the mode exctraction.Â The remaining solves will create additional load vectors.
resvec,on
modcont,on
F,num_NODE_,F_DOF_INDEX_,1Â Â Â !Generate the first load vector
solveÂ Â ! modal extraction and first load vector
F,num_NODE_,F_DOF_INDEX_,1 Â !Generate the second load vector
solveÂ Â ! create second load vector
F,num_Node...
solve
etc...
Â

 You must be logged in to reply to this topic.

461

220

194

177

162
Â© 2024 Copyright ANSYS, Inc. All rights reserved.