We have an exciting announcement about badges coming in May 2025. Until then, we will temporarily stop issuing new badges for course completions and certifications. However, all completions will be recorded and fulfilled after May 2025.

Ansys Innovation Space

FREE STUDENT SOFTWARE

I am trying to restart a transient CFX simulation from a previous results file. Before starting the simulation, I check the box “continue History from -> Initial Values” (or set the corresponding command line argument -continue-from-file), and as the initial value I select the last result file “oldResults.res”. The problem I have encountered is that the solver starts from the beginning (t_start=0 [s]) instead of really resuming the time (t_start = t_EndOfPreviousRun). However, it is correctly showing the history of the simulation. What could be the reason for this behavior?

- June 5, 2023 at 7:05 am
  
  FAQ
  Participant
  
  Probably you selected the option “Value = 0 [s]” for the initial time. Please check the CCL in the .out-File of your restarted run for the Keyword “INITIAL TIME, see the following sample CCL snippet: FLOW: Flow Analysis 1 &replace ANALYSIS TYPE: Option = Transient EXTERNAL SOLVER COUPLING: Option = None END INITIAL TIME: Option = Value Time = 0 [s] END TIME DURATION: Option = Total Time Total Time = 10 [s] END TIME STEPS: Option = Timesteps Timesteps = 1 [s] END END END The default option for “INITIAL TIME” would be “Automatic with Value”, “Time = 0 [s]”, which sets the initial time to zero if the run is not a restarted one, and to the final time of the previous run if the run is restarted. The option “Value” sets the initial time to zero even if it is a restarted run. Therefore, for a proper restart where the time is resumed from the previous simulation (t_start = t_EndOfPreviousRun), you must change the option for “INITIAL TIME” to “Automatic with Value”.

Add Tags

Share to Feed

Cancel Save Draft Post