Learning Forum

[ThomasDD]

Or is the only way to insert an APDL snippet?

[Gary_S]

Corrent. You must use the command object outres,all,all

But there is a caveat i want to mention:

Several release ago, changes were made to the OUTRES command in order to provide more granularity in how data was written to the results file (with the goal of reducing rst file size.) 

 Prior 2019R1, if the user requested say element stress results, they would also get say nodal temperatures (wasn't possible to disable nodal temps).
 2019R1 and later, the outres only returns results that are explicitly asked for.
 The benefit of this is that it allows the user to avoid writing (large) results files that contain perhaps unneeded data. 

Run a test case in WB Mechanical to see how the default outres commands are being written to the ds.dat input file.

The 2019R1 Release notes shows the following changes to OUTRES.
2.4.1. Enhanced Control of Solution Data Output

The OUTRES command has been restructured and eight new labels have been added to enable more
control over individual records written to the results file for each element. The command continues to
write all results (including those identified by the new labels) by default. If you disable all output
(OUTRES,ALL,NONE), however, and then selectively enable certain results, the newly labeled items are
no longer be written unless you request them (via multiple OUTRES commands). Also, the existing VENG
label (element energies) now properly follows this logic. For more information, see OUTRES. 

 

[mrife]

ThomasDD

In WB Mechanical go to File -> Options; Analysis Settings and Solution.  There are options to change what is written to the result file for each analysis type.  These are changes to the UI so the next time you run Mechanical, it will pick up these settings and so you could essentially recreate the outres,all,all behavior. 

[ThomasDD]

I have to use 2021 R2 and I need the elastic strain energy density (SEND:ELASTIC). It seems this output is only available if I use OUTRES,ALL,ALL for linear-elastic calculations (if elastic-plastic material, the elastic strain energy density is available by default)

If I set all Output Controls in Analysis Settings to "Yes" I don't get the SEND variable. It is available only if I use OUTRES,ALL,ALL