Reply To: How to carry out a transient analysis following on from a static analysis in ANSYS Mechanical APDL?

[Erik Kostson]

HI

You should use transient for all analysis (as you saw one can not switch), and in the first say one or two steps do not have a time integration (TIMINT command), which basically results in a static solution. AFter that in the last step you can turn them on and add dynamic loads as needed.

Below is an example of what I meant:
/SOLU
ANTYPE,TRANS
TRNOPT,FULL
TIMINT,OFF,ALL ! static solution no mass matrix and dynamic effects
TIME,1
DELTIM,0.1,0.1,0.1
SOLVE
ANTYPE,TRANS ! second step with integration and dynamic effects on so transient dynamic solution
TRNOPT,FULL
TIMINT,ON,ALL ! dynamic solution on
...
....
TIME,2
DELTIM,0.1,0.1,0.1
OUTRES,ALL,ALL
SOLVE
ANTYPE,TRANS
TRNOPT,FULL
TIMINT,ON,ALL ! dynamic solution on / transient effects
D,1,ALL,0
....
....
DELTIM,0.002,0.002,0.002
OUTRES,ALL,ALL
SOLVE